You are here:

Dowel Pin Hole Tolerances: Getting Alignment Right

Views: 1004 Publish Time:
Renjie Precision
Precision CNC Machining, Sheet Metal & Injection Moulding
specializes in precision CNC machining, rapid prototyping, sheet metal fabrication, laser cutting, plastic injection molding, and surface finishing
follow me on:


Dowel Pin Hole Tolerances: Getting Alignment Right

Dowel pins do one job: they put two parts back in exactly the same place every time they are assembled. They are not supposed to carry the load, and they are not supposed to be adjusted. That narrow job makes the hole tolerance surprisingly unforgiving — a dowel hole that is 0.01 mm off in size, or 0.05 mm off in position, can make an otherwise perfect assembly impossible to put together.

This guide covers the fits that actually work, why one hole should be tight and the other loose, and the positional tolerance that matters more than the diameter callout.

The Short Answer

For a steel dowel pin locating two machined parts, use H7/m6 for the press-fit hole and H7/h6 (or H7/g6) for the slip-fit hole — and never press-fit both holes in the same assembly.

FitHolePinResultTypical use
Press / interferenceH7m6Pin held permanently in one partThe fixed half of the assembly
TransitionH7k6Light press, may be looseRarely worth the ambiguity
Slip / clearanceH7h6Pin slides in by handThe removable half
Free clearanceH7g6Small guaranteed gapFrequent disassembly, dirty environments

Standard dowel pins are made to m6 (or h6 for some series), so the designer's real decision is the hole. Ream to H7 and the fit follows.

The Two-Hole Rule

This is the most common dowel pin mistake, and it is worth stating plainly: if both holes are press fits, the parts usually will not assemble. Two interference-fit pins create an over-constrained joint. Any error in the centre distance between the two holes on either part — even 0.02 mm — has nowhere to go, and the pins bind halfway in.

The standard arrangement is:

  • One hole press-fit (H7/m6) — the pin stays in that part permanently and acts as the datum.
  • One hole slip-fit (H7/h6 or H7/g6) — the mating part drops over the pin with a few microns of clearance, which absorbs centre-distance error.

Two pins are still enough to fix rotation and translation. A single pin would allow the parts to pivot; three pins reintroduce over-constraint. Two is the correct number for almost every assembly.

If both parts must be removable, use slip fits in both holes and retain the pins with a cover plate or a threaded retainer. Our DFM rules for machined parts covers related assembly constraints.

Hole Size: Reaming, Not Drilling

H7 is a reamed tolerance, not a drilled one. A twist drill — even a good one, even on a machining centre — typically produces H11 to H13 with a bell-mouthed entry and a slightly tapered hole. Reaming (or fine boring, or a reamer-type interpolated toolpath on a good machine) is what gets you to H7.

Nominal pinH7 hole limitsm6 pin limitsResulting interference
Ø3 mm3.000 – 3.0103.002 – 3.0100 – 0.010 mm
Ø5 mm5.000 – 5.0125.004 – 5.0160 – 0.016 mm
Ø6 mm6.000 – 6.0126.004 – 6.0160 – 0.016 mm
Ø8 mm8.000 – 8.0158.006 – 8.0210 – 0.021 mm
Ø10 mm10.000 – 10.01510.006 – 10.0210 – 0.021 mm
Ø12 mm12.000 – 12.01812.007 – 12.0250 – 0.025 mm

Note that H7/m6 is a transition fit: the interference can be zero at the limit. For a pin that must never fall out, specify H7/p6 or use a retaining compound. For a pin that must be removable by hand, H7/h6 gives a minimum clearance of zero and a maximum of roughly twice the hole tolerance.

Blind holes need an escape

Pressing a pin into a blind hole traps air. The pin acts as a piston, and on a close fit it simply will not seat fully — or it hydraulically pushes the part off the fixture. Add a small vent hole, a flat on the pin, or specify a through hole. This detail is missed more often than any tolerance in this article.

Positional Tolerance Matters More Than Diameter

A part with two perfect H7 holes 0.10 mm out of position will not assemble. A part with two slightly loose holes in exactly the right place usually will. Position is the dominant error source, and it is the one drawings most often omit.

For a two-pin assembly, define the hole pattern with a true-position callout referenced to the same datums on both parts — typically the primary mounting face and two adjacent edges, or the same bore. A practical starting point is Ø0.02–0.05 mm true position at MMC for precision assemblies, loosening to Ø0.1 mm for general fabrication.

Using the same datum scheme on both parts is essential. If part A locates the holes from its left edge and part B from its right edge, edge-to-edge variation propagates directly into pin misalignment even if each part is individually in tolerance. Our machining tolerances guide explains how datum choice and MMC interact.

Centre distance is a derived dimension

Avoid dimensioning the distance between the two dowel holes as a standalone ± tolerance. Chain dimensioning accumulates error. Dimension each hole from the datums with true position instead, and let the centre distance be a reference dimension. If a centre distance must be given, make it a basic (boxed) dimension with position controlling the variation.

Material and Temperature Effects

A steel pin in an aluminum housing is a classic trap. Aluminum expands at roughly 23 µm/m·K versus 12 µm/m·K for steel. Across a 30 °C temperature swing, a 100 mm pin span in aluminum grows about 0.033 mm more than the steel pins — enough to turn a comfortable slip fit into a binding one, or a light press into a loose one.

CombinationConcernMitigation
Steel pin / steel partMinimalStandard fits apply
Steel pin / aluminum partDifferential expansion, gallingLooser slip fit, specify assembly temperature
Steel pin / stainless partGalling on pressLubricate, avoid repeated pressing
Steel pin / plastic partCreep, cold flowUse a metal insert or larger bearing area
Aluminum pin / aluminum partWear on repeated assemblyHarden or use steel pins

For parts that see a wide temperature range, either match the pin material to the housing or shift the fit toward clearance. Specify the temperature at which fit is verified — 20 °C is the standard reference, and it is worth stating.

Surface Finish and Hole Geometry

Reamed H7 holes should be Ra 0.8–1.6 µm. A rougher finish effectively reduces the interference on a press fit (the peaks flatten on insertion) and accelerates wear on a slip fit. Reamers also leave a characteristic straightness and roundness that a single-point boring pass can match but a drill cannot.

Two geometric errors are worth checking on the first article:

  • Bell mouthing at the hole entrance, caused by a reamer that is not perfectly aligned with the pilot hole. It produces a fit that feels loose at the top and tight at the bottom.
  • Hole taper, caused by reamer deflection or a worn tool. Measure at two depths, not just at the mouth.

Both are reasons to ream the two mating parts in the same setup, or at least with the same fixture and the same tool, whenever the assembly is critical. This is standard practice for tooling plates and inspection fixtures.

Common Failure Modes

Pins will not start

Both holes press-fit, or the hole pattern position is out. Check position first, then the fit. Deburr the hole mouths — a 0.05 mm burr is enough to stop a close-fitting pin.

Pins fall out

H7/m6 at the loose limit gives zero interference. Use H7/p6, a retaining compound, or a stepped pin. Never "fix" it by hammering a larger pin into an H7 hole.

Assembly is tight in the cold, loose when warm

Differential thermal expansion with a steel pin in aluminum. Widen the slip fit and specify the verification temperature.

Pin shears in service

The pins are being asked to carry load they were never sized for. Dowels locate; bolts clamp. Add clamping fasteners or increase pin diameter rather than tightening the fit.

Frequently Asked Questions

What tolerance should a dowel pin hole be?

H7 is the standard. Ream it — a drilled hole will not hold H7. Pair it with an m6 pin for a press fit or an h6 pin for a slip fit.

Should both dowel holes be press fit?

No. Press-fit one hole so the pin stays in that half, and slip-fit the other. Two press fits over-constrain the assembly and small centre-distance errors will prevent it from going together.

Can I drill a dowel hole instead of reaming it?

Only for loose, non-critical locating. Drilled holes are typically H11–H13 with poor roundness and a bell-mouthed entry, so the pin will either wobble or bind unpredictably.

How accurate does the hole position need to be?

For precision assemblies, Ø0.02–0.05 mm true position at MMC referenced to shared datums. For general fabrication, Ø0.1 mm is usually fine. Position error causes more assembly failures than hole size error.

Why does a pin not seat fully in a blind hole?

Trapped air. The close-fitting pin acts as a piston. Add a vent hole, use a pin with a flat, or make the hole a through hole.

Dowel pin problems are almost always cheap to design out and expensive to discover at assembly. If the fit, the datum scheme, and the two-hole rule are settled before the drawing is released, the pins simply do their job quietly. For a wider view of how hole callouts affect inspection cost, see our quality control guide.